Instruction for part program generating
using KSPT/KSPF package
1. Description of geometry
1.1. Geometrical elements
Element Positions of geometrical elements (coordinates or definition method)
number X [mm] Z [mm]
P1 0 0
P2 8 0
L1 Line through P1 and P2 points
P3 10 -2
L2 Horizontal line through P3 point
L3 Vertical line Z=-30
P4 Intersection point of L2 and L3 lines
L4 Vertical line Z=-40
L5 Horizontal line X=15
P5 Intersection point of L2 and L4 lines
P6 Intersection point of L4 and L5 lines
L6 Vertical line Z=-60
L7 Line at the angle of 45o to horizontal direction
P7 Point on L7 line with coordinate Z=-50
C1 Circle with centre in P7 point and radius R=10
P8 Intersection point of C1 circle and L5 line
P9 Intersection point of C1 circle and L6 line
P10 Intersection point of L6 and L7 lines
L8 Horizontal line X=55
P11 Intersection point of L7 and L8 lines
L9 Vertical line Z=-160
P12 Intersection point of L8 and L9 lines
L10 Vertical line Z=-170
P13 Intersection point of L8 and L10 lines
L11 Horizontal line X=60
P14 Intersection point of L10 and L11 lines
P15 Intersection point of L1 and L11 lines
Base point coordinates X = 80, Z = 20
1.2. Description of contours
1.2.1. Contour for finishing  O1
Geometry/Contour/1.Define
Input No:1, click on the arrow and choose Point No.
Repeat operation for points: P2, P3, P5, P6, P8, P9, P10, P11, P13, P14
Allowance D=1 (to use in roughing contour O11)
Finish contour definition by pressing END button.
1.2.2. Contour for roughing  O11
Geometry/Contour/B.Allowance contour
Nr:11, O:1, Str:-1 (allowance contour will be placed upper and on right)
1.3. Base point coordinates
Edit, write BAS/ZS20,XS80
2. Technology
2.1. Tools definition
2.1.1. Facing and Roughing
Technology/Tools/Definition
Choose the right cutter (roughing/finishing cutter - form cutter - grooving cutter - drill)
- Tool No: 1,
- Identifiers of - tool1: 71.26 RA 3225,
- Insert: TNMG 2204,
- Holder: - ,
- Insert material: S10,
- Total length: 150,
- Width * Height: 3225,
- Z: -36,
- X: -150,
- R: 0.8,
- Characteristic Point No: 0,
- Tool cutting edge angle: 93,
- Auxiliary tool cutting edge angle: 27.
2.1.2. Finishing
Technology/Tools/Definition
Choose the right cutter (roughing/finishing cutter - form cutter - grooving cutter - drill)
- Tool No: 2,
- Identifiers of - tool1: NNWd 3225
- Insert: -,
- Holder: - ,
- Insert material: S10,
- Total length: 150,
- Width * Height: 3225,
- Z: -30,
- X: -150,
- R: 0.1,
- Characteristic Point No: 0,
- Tool cutting edge angle: 100,
- Auxiliary tool cutting edge angle: 50.
2.1.3. Threading
Technology/Tools/Definition
Choose the right cutter (roughing/finishing cutter - form cutter - grooving cutter - drill)
- Tool No: 3,
- Identifiers of  tool: NNGr 3225,
- Insert: -,
- Holder: - ,
- Insert material: S10,
- Total length: 150,
- Width * Height: 3225,
- Z: -27,
- X: -150,
- 60.
2.2. Operations  Tool path generating
2.2.1. Facing
a) Cutting parameters - Technology/Cutting parameters:
- Feed 0.1 mm/rev
- Rotational speed 355 rev/min
- Coolant on
- Direction of revolutions CCW
b) Tool calling  Technology/Tools/Calling
Click on required tool, assign tool number, position in head and corrector number.
Choose upper head and return to base.
c) Tool path in  Operation mode  Technology/Machining/Operations
- click dashed arrow (positioning movement), Coordinates Z=0, X=61,
- click continuous arrow, Coordinates Z=0, X=0,
- click dashed arrow, Coordinates Z=20, X=80.
2.2.2. Roughing
a) Tool calling  Technology/Tools/Calling
b) Tool path in  Cycle mode  Technology/Machining/Cycles
- choose the  roughing icon,
- Ending Contour No 11,
- Starting Contour No -- (default dimensions of workpiece),
- Max. depth of machining 3 [mm],
- Approach value 1,
- Choose Feed directions and Cycle type,
- click OK and input cutting parameters: Feed 0.3 mm/rev, Revolutions 450 rev/min.
2.2.3. Finishing
b) Tool calling  Technology/Tools/Calling
b) Tool path in  Cycle mode  Technology/Machining/Cycles
- choose the  finishing icon,
- Contour No 1,
- Approach value 1,
- Retract value 1,
- Allowance 1,
- Engagement angle 0,
- Disengagement angle 0,
- Choose Type of contour,
- click OK and input cutting parameters: Feed 0.1 mm/rev, Revolutions 560 rev/min.
2.2.4. Threading
c) Tool calling  Technology/Tools/Calling
b) Tool path in  Cycle mode  Technology/Machining/Cycles
- choose the  threading icon,
- click metric,
- click standard,
- click constant pitch,
- click external,
- click radial feed,
- click Constant chip section,
- click OK and input other parameters:
- Initial thread diameter 20
- Starting Point No 3,
- Ending Point No 4,
- Approach value 1,
- Retract value 3,
- Move back value 1,
- Number of passes 10,
- click Slantwise engagement,
- click OK and input cutting parameters: Feed 2.5 mm/rev, Revolutions 180 rev/min.
2.3. Simulation according to CLData
Save CLData file (File/Save CLD.DTA) and simulate cutting (Simulators/Simulation).
2.4. Generating part program for CNC machine tool
Choose the right postprocessor (Postprocessors/List of postprocessors) and follow the
instructions to finish the part program.
2.5. +3+
2.6.+
2.7. Simulation according to part program  Simulators/ISO code pgm simulation
3. Elaboration of part geometry and technology using
 Group Technology mode
a) start polish version of KSPT/KSPF package,
b) choose  Technologia grupowa (Group Technology) option  Technologia/Obróbka,
Technologia grupowa,
c) click Wałki (Shafts) and choose the most similar part,
d) input the right dimensions according to drawing symbols,
e) generate the part program for CNC machine tool.